Pulling

1 Select the Pull tool from the Edit ribbon group.

Mouse over faces and edges in your design to preview the natural Pull direction. If your mouse is over multiple faces or edges, use the scroll wheel to preview the Pull direction for each one.

2 Select the faces and/or edges you want to pull to create 3D solids or surfaces.

You can right-click in the Design window and select Anchor Pull Handle, then click to anchor the Pull handle on another object. This command is useful when you want to dimension a Pull from a different location than the center of a face.

3 (Optional) Alt+click to select the face or edge that will drive the change.

You can also select the appropriate tool guide, then click the face or edge. The driving edge or face is shown in blue. If you select the Show cursor arrows SpaceClaim option, arrows appear to indicate the directions you can move your mouse to edit the selected object.

4 (Optional) Select options from the Options panel, or right-click and select them from the mini-toolbar.

5 Click and drag in the direction of the Pull arrow to create or edit a solid.

If the correct pull arrow is not highlighted, press Tab or click the Pull arrow you want to use.

Press Shift to snap while pulling.

To dimension the pull, type the distance you want to pull and press Enter. (If the dimension field does not appear editable, start typing while you are pulling to enter the dimension.)

You do not have to click and drag on (or even near) the Pull arrow. In fact, we recommend that you move your cursor away from the arrow for more precise control of the pull. The only important input to the Pull tool is the direction in which you are moving the cursor. When you pull, contiguous solids are automatically combined.

If you want to pull in a head-on view, use the ruler at the bottom right corner of the Design window to pull instead of the Pull arrow. Slide the gray bar to the left to subtract material, and to the right to add material.

You can also click the Up To tool guide, then click the object that sets the plane up to which you want to pull. (When pulling an edge, the face does not need to intersect the edge you are pulling.)

If you pull through another object in the same component, the smaller object is merged into the larger one, and receives the larger object's properties. If you pull multiple, touching surfaces, the smaller surfaces are merged into the largest one.

Press Esc to cancel the Pull.

See the topics in the Table of Contents under Designing > Editing > Pulling for the list of actions you can perform with the Pull tool.

Editing with the Pull tool

Use the Pull tool to offset, extrude, revolve, sweep, draft, and blend faces; use it to round, chamfer, or extrude edges. You can select a face, then pull, dragging anywhere to act, or you can click, drag, and release a highlighted face. In general, the result of a pull stays selected or highlighted after the pull operation.

The action of the Pull tool depends on which faces and edges you select to work with, and which faces, planes, or edges you select to drive the change. For example, if you choose to work with a face, then select an edge to "drive" the pull, the Pull tool infers that you want to pivot the face around that edge. When multiple actions can be inferred, you can use the tool guides to correct the Pull tool's inference. The Pull tool maintains any offset, mirror, pattern, or coaxial relationships.

When you pull a face, there are two main decisions you need to make. The first is to determine the direction you want to pull in. A default direction is offered to you, but it can be overridden using the Direction tool guide. The second is to determine what is going to happen at the edges of the face. By default, the edges of the face are determined by its neighbors, but you can override this behavior by including the edges in your Pull selection to create an extrusion.

Within the Pull tool, there are several tool guides that let you specify the behavior of the Pull tool:

The following options are available in the Pull tool. Once you select the edge or face to pull, select these options from the Options panel, or right-click and select them from the mini-toolbar:

	The Select tool guide is active by default. When this tool guide is active, you can perform standard selection tasks, and create natural offsets and rounds. Select a face, parallel faces, or surface edges to offset them. Select a solid edge to round it. Alt+click to select the driving face or edge for revolves, directed extrusions, sweeps, and drafts. Alt+double-click an edge to select an edge loop. Alt+doube-click again to cycle through alternate edge loops. You can select objects across multiple components to pull.
	Select a face to pivot or select a face and edge to revolve. Then use the Rotate tool guide to select the straight line, edge, or axis around which you want to pivot or revolve.
	Use the Direction tool guide to select a straight line, edge, axis, origin axis, plane, or planar face to set the pull direction.
	Use the Sweep tool guide to select the straight or curved lines or edges along which you want to sweep. Faces and edges can be swept, and the sweep trajectory cannot be in the same plane as the face.
	Select any number of contiguous faces on the same body, then use the Draft tool guide to select the plane, planar face, or edge around which you want to pivot. None of the contiguous faces can be parallel to the neutral plane, face or edge around which you want to pivot.
	Use the Up To tool guide to select the object that you want to pull to. The pulled object's face or edge will mate with the surface of the selected body or be pulled up to a plane through the selection.

Add	Select the Add option to only add material. If you pull in a subtractive direction, no change will occur. You can combine this option with other Pull options.
Cut	Select the Cut option to only remove material. If you pull in an additive direction, no change will occur. You can combine this option with other Pull options.
Pull Both Sides	Select a single, detached edge, imprinted edge, or surface, then click this option to pull both sides of the edge or surface at once.
Full Pull	Once you select the edge about which to revolve or sweep, click this option to revolve 360 degrees or to the next face, sweep through the full trajectory, or blend through selected faces.
Create Ruler Dimension	Select this option, then click to connect a ruler, oriented along the pull axis, to an anchor edge or face. You can use the ruler to dimension the pull. The direction must be specified to successfully create a ruler dimension. Press Esc to cancel the ruler dimension.
Round	When you are pulling an edge, select this option to create a fillet.
Chamfer	When you are pulling an edge, select this option to create a chamfer.
Extrude Edge	When you are pulling an edge, select this option to extrude the edge into a surface.
Copy Edge	When you are pulling an edge, select this option to create a copy of the edge.
Pivot Edge	When you are pulling an edge, select this option to pivot the edge along the selected Pull arrow.
Maintain Offset	Select this option to maintain the offset relationship when pulling.
Blend	Select this option to create a blend between the selected faces, surfaces, or edges when you pull.
Rotational Blend	Select this option to create cylinders and cones whenever possible during the creation of a blend.
Periodic Blend	Select this option to go all the way around when blending.
Show Take-Off Vectors	Select this option to show the vectors created by maintaining tangency of neighboring faces and edges when blending. This option is especially useful when blending between edges.
Revolve Helix	Select this option to create a helix.
Right-Handed Helix	Select this option to determine the direction in which the helix is revolved around its axis.
Rotational Rib	Select this option to pull a rib in a rotational direction.
Normal to Trajectory	Select this option to keep every portion of the swept geometry normal to the sweep trajectory.
Draft Both Sides	Select this option to pivot the face on the opposite side of the reference face as well as the selected face.

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