a   Select New > New Design from the Application menu  to create a new design.

A blank design containing the sketch grid is displayed in a new Design window. The mode is set to Sketch, since that is usually the first step to create a new design.

The following figure shows some of the interface elements referred to in this tutorial.

 

b   Select Save from the Application menu to name and save your design.

The name of your design appears as the top-level component in the Structure tree.

a  Click SpaceClaim Options in the Application menu .

b  Click Units.

c   Select Imperial from the Type drop-down.

Inches appear in the Length drop-down, the minor grid spacing changes from .1mm to 1/8 in, and the minor grid lines per major changes from 10 to 8. This means that you can dimension in inches, and that the sketch grid lines are now spaced 1/8 inch apart, and the darker grid lines appear every inch.

d   Select Decimal from the Decimal/fraction drop-down.

e   Click OK.

a   Sketch a rectangle that will become the bottom piece of the bracket.

1  Click the Rectangle tool in the Sketch ribbon group on the Design tab.

2  Click to set the first corner of the rectangle.

As you move your mouse, a preview of the rectangle is drawn, and dimension fields appear.

3  Enter 1.125, then press Tab and dimension the second side by entering 4.281.

If you make a mistake, click a dimension to edit it. Or click the Select tool  in the Edit ribbon group and double-click the rectangle to select it. Then press Delete to delete the rectangle and redraw it.

3  Press Enter to complete the rectangle.

b   Pull the rectangle into 3D to create the bottom of the bracket.

1  Switch to 3D mode by clicking the 3D mode tool in the Mode ribbon group.

The Pull tool  in the Edit ribbon group is activated, your sketched rectangle now appears as a rectangular surface, and the surface appears in the Structure tree.

2  Click on the face of your rectangular surface to select it.

The faint yellow cursor arrows show you the directions in which you can pull the rectangle.

3  Drag to begin thickening the rectangle.

You can drag with your cursor anywhere in the Design window – you do not have to drag on the Pull arrow itself. We recommend that you move your mouse off to the side when pulling to make it easier to see your changes.

4  Enter .483 and press Enter to dimension the pull.

The surface in the Structure tree is replaced by a solid.

a   Extrude an edge to form a surface.

1  Click the back edge of the solid with the Pull tool to select it.

The edge is highlighted and edge options appear in the Options panel and mini-toolbar. Move your mouse closer to the mini-toolbar to make it more opaque.

2  Select the extrude edge option in the Options panel.

(You can hover over any option to display a tooltip that explains the option.)

The Pull arrows change to indicate the two default directions in which you can extrude the edge.

3  Click the vertical arrow and drag the edge upward to begin creating a surface.

4  While dragging, press and release the spacebar to display a dimension field.

5  Enter 1.4.

6  Press Enter to complete the surface.

This surface now appears in the structure tree, below the solid.

b   Pull the surface into 3D.

1  Click the surface you just created to select it.

2  Drag toward the front of the solid.

3  Enter .483 to match the thickness of your first solid.

4  Press Enter to finish pulling and create the surface.

In the Structure tree, the surface disappears and this new solid is automatically merged with the first.

a   Round the inside corner of the bracket.

1  Click the edge on the inside corner of the bracket with the Pull tool.

2  Click the Round Edge pull option in the Options panel.

3  Drag away from the solid to round the edge.

4  While dragging, press and release the spacebar to display a dimension field.

5  Enter .2.

6  Press Enter to finish pulling and create the round.

b   Round the outside corner of the bracket.

1  Turn the bracket so you can see the bottom by clicking the Spin tool in the Orient ribbon group and dragging to spin your design.

Another way to spin is to mouse over an edge in your design. Then press Alt and drag with the middle mouse button to spin your design around that edge. Spinning in this way lets you keep the Pull tool active.

2  Click the Pull tool, then click the edge that forms the outside corner of the bracket.

3  Drag into the solid to round the edge.

4  While dragging, press and release the spacebar to display a dimension field.

5  Enter .4.

5  Press Enter to finish pulling and create the round.

6  Click Home in the Orient ribbon group to view the design in trimetric view.

If you modified the default Home view, you can press Alt+left arrow or click in the status bar to return to your previous view.  

a   Sketch a dimensioned point on the top face of the bottom piece of the bracket.

1  Click the Select tool in the Edit ribbon group and click the top face of the bottom piece of the bracket to select it.

2  Click the Point tool in the Sketch ribbon group.

You are now in Sketch mode. The sketch grid appears and the Sketch mode tool is active in the Mode ribbon group.

Because you entered Sketch mode with a face selected, SpaceClaim assumes you want to sketch on that face, and orients the sketch grid along that face.

3  Click Plan View in the Orient ribbon or the mini-toolbar to view the sketch grid head-on.

4  Place the cursor over the bottom left vertex of the face, press and release Shift, then move your mouse toward the back of the bracket along the right edge. Do not press the mouse button.

A dimension field appears. (You can “Shift+touch” any object in any tool to dimension from that object.)

5  Press and release the spacebar to dimension the point’s distance from the vertex.

Enter 1.5.

6  Press Enter to create the point.

If the point was created at the wrong place, you can press Ctrl+Z or click  in the Quick Access toolbar (on the left side of the SpaceClaim title bar) to try again.

 

 

 

 

a   Draw an angled line.

1  Click the Line tool in the Sketch ribbon group.

2  Click the point you created in the previous step.

3  Move the mouse towards the end of the bracket. Do not hold a mouse button.  

Two dimensions appear, one for the line’s length, and one for the angle formed between the sketch grid’s Y axis and the line.

4  Press and release the spacebar to dimension the line. Press Tab to switch to the angle dimension.

Enter 13.

5  Press Tab and continue moving the mouse until it intersects with the end of the bracket.

The edge that forms the end of the bracket highlights when the line intersects with it.

6  Double-click to end the line.

If the line tool continues to draw line segments, press Esc or right-click and select Finish Line.

 

 

 

 

 

 

 

 

3   Remove material from the bracket.

a  Click Home in the Orient ribbon group to view the design in trimetric view.

b  Click the Pull tool in the Edit ribbon group.

You are now back in 3D mode. The 3D mode tool is active in the Mode ribbon group.

c  Click the triangular region created by the line and the edge of the bracket.

d  Drag downward until all the material is removed.

Notice that as you pull through the solid of the bracket, the Pull tool assumes that you want to remove material, and the cursor changes to  indicate that the pull is subtractive.

a   Sketch a dimensioned point on the side face of the bracket.

1  Turn the bracket so you can see the side opposite from the side you just removed material from by dragging with the middle mouse button. (You can also click the Spin tool   in the Orient ribbon group and drag to spin your design or select Right from the Trimetric tool menu.)

Click Pan in the Orient ribbon group to reposition the bracket within the Design window.

2  Click the Select tool in the Edit ribbon group and click the side face of the bracket to select it.

3  Click the Point tool in the Sketch ribbon group.

You are now in Sketch mode. You can tell you are in Sketch mode because the sketch grid appears, and the Sketch mode tool is active in the Mode ribbon group.

Because you entered Sketch mode with a face selected, SpaceClaim assumes you wanted to sketch on that face, and orients the sketch grid along that face.

4  Click Plan View to view the sketch grid head-on.

5  Place the cursor over the vertex at the end of the bracket, press and release Shift, then move your mouse toward the back of the bracket along the edge. Do not press the mouse button.

A dimension appears. (You can “Shift+touch” any object in any tool to dimension from that object.)

6  Press and release the spacebar to dimension the point’s distance from the vertex.

Enter 1.5.

7  Press Enter to create the point.

If the point was created at the wrong place, you can press Ctrl+Z or click   in the Quick Access toolbar (on the left side of the SpaceClaim title bar) to undo and  try again.

 

 

b   Draw a line that will become the edge to pivot around.

1  Click the Line tool in the Sketch ribbon group.

2  Click the point you created in the previous step.

3  Move the mouse until the line is drawn at 90 degrees from the top to the bottom of the bottom piece of the bracket.

4  Double-click to end the line.

If the line tool continues to draw line segments, press Esc or right-click and select Finish Line.

 

 

 

 

 

 

c   Revolve the face to match the angled face on the other side of the bracket.

1  Click the Pull tool in the Edit ribbon group.

You are now in 3D mode. The 3D mode tool is active in the Mode ribbon group.

2  Turn the bracket so you can see the side and top of the bracket by clicking the Spin tool   in the Orient ribbon group and dragging a small amount to spin your design.

3  Click the Pull tool again and click the face between the pivot line and the end of the bracket.

4  Click the Revolve tool guide (located on the right side of the Design window).

5  Click the pivot line.

The line is highlighted in blue and the Pull arrow changes to show that pulling will revolve the selected face.

6  Drag to begin revolving the face.

7  While dragging, press and release the spacebar to dimension the revolve.

Enter -13.

8  Press Enter to finish the revolve.

a   Round the angled end of the bracket.

1  Click in the empty space in the Design window to clear your previous selections.

2  Click one of the edges at the end of the bracket to select it.

Notice that the round edge option is selected by default, since the Pull tool assumes from your selection that you want to round the edge.

(You can drag with the middle-mouse button to quickly spin your design.)

3  Ctrl+click the other edge to add it to your selection.

4  Drag into the solid to round both edges simultaneously. Continue dragging until the rounds meet in the center to form a full round.

a   Create a circle at the end of the bracket.  

1  Click the Select tool in the Edit ribbon group and click the top face of the bottom piece of the bracket to select it.

2  Click the Circle tool in the Sketch ribbon group.

You are now in Sketch mode. You can tell you are in Sketch mode because the sketch grid appears, and the Sketch mode tool is active in the Mode ribbon group.

Because you entered Sketch mode with a face selected, SpaceClaim assumes you wanted to sketch on that face, and orients the sketch grid along that face.

3  Click Plan View in the Orient ribbon group to view the sketch grid head-on.

The center of the arc created by the full round is shown with a cross.

4  Click the center of the arc and drag to begin sketching a circle.

5  While dragging, press and release the spacebar to dimension the pull.

Enter .3.

6  Press Enter to create the circle.

 

 

2   Pull the circle to create a hole in the end of the bracket.  

1  Click the Pull tool in the Edit ribbon group.

You are now in 3D mode. The 3D mode tool is active in the Mode ribbon group.

2  Turn the bracket so you can see the side and top of the bracket by dragging slightly with the middle mouse button.

3  Click on the circular region to select it.

4  Drag downward until all the material is removed.

Notice that as you pull through the solid of the bracket, the Pull tool assumes that you want to remove material, and the cursor changes to indicate that the pull is subtractive. If you pull away from the solid, it will add material.

5  Drag with the middle mouse button to spin the bracket so you can see through the hole.

a   Sketch a construction line so you can center a hole on the angle points.

1  Click the Select tool in the Edit ribbon group and click the top face of the bottom piece of the bracket to select it.

2  Click the Construction line tool in the Sketch ribbon group.

You are now in Sketch mode. The sketch grid appears and the Sketch mode tool is active in the Mode ribbon group.

Because you entered Sketch mode with a face selected, SpaceClaim assumes you wanted to sketch on that face, and orients the sketch grid along that face.

3  Click Plan View to view the sketch grid head-on.

4  Click the vertex on one side of the angled part, then click the vertex on the opposite side.

The cursor snaps to each vertex and it is highlighted in green. A dotted construction line appears.

 

 

b   Sketch a circle at the midpoint of the construction line.

1  Click the Circle tool in the Sketch ribbon group.

Mouse over the construction line. A triangle indicates the line’s midpoint.

2  Click the triangle and move the mouse slowly, until the existing hole is highlighted.

3  Release the mouse button to create a circle that matches the diameter of the first hole.

 

 

c   Pull the circle to create the second hole.

1  Click the Pull tool in the Edit ribbon group.

2  Click Home in the Orient ribbon group to view the design in trimetric view.

3  Click on the circular region to select it.

4  Drag downward until all the material is removed.

5  Drag with the middle mouse button to spin the bracket so you can see through both holes.

Notice that the construction line is converted to an axis, and now appears in the structure tree.

6  Uncheck the axis in the Structure tree to hide it.

You can also remove the sketched points by clicking them with the Select tool, then pressing Delete.

a   Create a pattern with the Move tool.

1  Click the Move tool in the Edit ribbon group.

2  Check the Create Patterns option in the Options panel.

3  Click the hole that is centered on the angle points.

To make this easier, zoom into your design by selecting Zoom Extents from the Zoom tool menu.

The Move handle is aligned along the axis.

4  Click the Move handle axis that is pointing away from the back of the bracket.

5  Press Ctrl and drag almost to the round at the back of the bracket.

6  Release Ctrl and the mouse button.  

A pattern count parameter is displayed, along with the dimension from the original hole to the copied hole.

 

 

 

 

a   Edit the pattern.

1  Enter 4 as the count.  

Four identical, equidistant holes appear on the bracket surface. These holes are now part of a pattern. The dimension between each hole in the pattern is now displayed as well as the other parameters.

Changes made to one hole will now affect all the others in the pattern. For example, if you click the Pull tool and select an axis of one of your holes, then drag, you can see all the holes change to slots. (Press Ctrl+Z to undo your change.)

a   Chamfer the top edge.  

1  Click the Pull tool in the Edit ribbon group.

2  Select the chamfer edge option .

3  Double-click one of the top edges to select the edge loop.

If the wrong edge loop is selected, double-click to select an alternate loop.

4  Drag into the solid to begin chamfering the edge.

5  While dragging, press and release the spacebar to dimension the chamfer’s setback.

Enter .1.

6  Press Enter to finish pulling and create the chamfered edges.

b   Press Ctrl+S or select Save from the Application menu to save your design.

a   Get the knob model.

1  Select SpaceClaim Options from the Application menu .

2  Click Resources.

3  Click Get Models to display the SpaceClaim Model Library on the SpaceClaim website.

4  Find the TutorialKnob.scdoc file and click Download.

b   Insert the knob component.

1  Click the Insert tool in the Insert ribbon group to display the Open Design window.

2  Navigate to and select TutorialKnob.scdoc and click Open.

The knob appears in the Design window inside the outline of a red box with the Move tool active to move it to a better position.

c   Move the knob so its small end is pointing at the back of the bracket.

1  Turn the bracket and knob so you can see their sides by clicking the Spin tool in the Orient ribbon group and dragging to spin your design.

2  Click an arrow of the Move tool and drag the knob until it is far enough past the bracket so you can turn it on its side.

3  Click the curved arrow of the Move tool and drag the knob until it is pointing toward the back of the bracket.

d   Activate the bracket component.

1  Mouse over the top-level structure in the Structure panel.

2  Right-click and select New Component. A new component, Component1, appears in the structure tree and is in bold, indicating it is activated.

3  Right-click the new component, Component1, click Rename, and name the new component Bracket. It appears in bold to indicate that it is the active component.

4  In the Structure tree, drag the first component under the top level of the structure, Solid, and drop it on the new Bracket component. You now have an ordered structure for your design.

5  In the Structure tree, right-click the top-level component and select Activate Component. The top-level component is now active, making both subcomponents active.

a   Activate the knob as a component, preparing to work on it by itself.

1  In the Structure panel, mouse over the knob component.

A red box appears around the knob.

2  Right-click and select Activate Component.

 

 

b   Create a pattern of grooves with the Move tool.

1  Turn the knob so you can see the whole groove, including the end where it joins the knob, by clicking the Spin tool in the Orient ribbon group and dragging to spin your design.

To make this easier, zoom into your design by selecting Zoom Box In from the Zoom tool menu in the Orient group.

2  Check Create Patterns in the Move Options panel.

3  Click the Select tool in the Edit ribbon group and click both surfaces of the groove. Ctrl+right-click on both surfaces.

4  Re-anchor the Move tool to a central axis so you can copy the groove by dragging the center of the Move handle, or using the Anchor tool guide -  select the Anchor tool guide (on the right of the Design window), then click on the axis in the center of the knob.

5  Press Ctrl and drag with the right mouse button slowly along the blue rotate arrow.

SpaceClaim gives you its best idea of what you would like for a pattern. It stops at 45°. If you kept going it would snap to a 60° pattern.

 

 

c   Remove unwanted space with the Fill tool in the Edit ribbon.

1  Rotate the knob so you can see the fillet under the head of the knob.

2  Click on the Select tool  in the Edit ribbon group then click on the fillet.

3  Click on Fill tool in the Edit ribbon

The fillet becomes flat.

a   Measure the small cylinder on the end of the knob.

1  Zoom out of your design by selecting Zoom Out from the Zoom tool menu.

2  Click the Measure tool in the Analysis ribbon, then click on the small cylinder.

You will see measurements for the circle diameter (3/8 in), circle perimeter (1.178 in) and angle between adjacent surfaces (90°).

Click on other parts of the model to see their dimensions.

 

 

b   Create a hole in the back of the bracket so you can insert the knob into it.

1  Right-click Bracket in the Structure panel and select Activate Component from the drop-down menu.

A red box appears around the Bracket.

2  Pan over to the bracket and spin it so you can see the back of its wall and the knob.

3  Click the back of the bracket then click the Sketch Mode tool in the Mode ribbon. The grid appears on the back of the bracket.

4  Click the Display tab above the ribbon.

In the Grid group, click Clip Scene Above Grid. The knob temporarily disappears.

5  Return to the Design tab and click the Trimetric tool from the Orient ribbon, and select Back from the menu. The back of the bracket faces you.

 

 

c   Use a construction line to locate the hole in the center of the back.

1  Click the Construction line tool in the Sketch ribbon group.

Move the cursor over the top line. It snaps to the center of the line. Be careful to click on the top of the back and not on the top of the chamfer.

2  Drag to draw a construction line to the bottom of the surface.

The line snaps to the center of the bottom edge. Press Esc to exit the tool.

3  Click the Circle tool in the Sketch ribbon group and move the mouse over the top of the construction line. (Do not press a mouse button.)

4  Press and release the Shift key to dimension from another point, then move the mouse slowly in the direction you want to place the circle. In the dimension box, type the value where you want to locate the circle center (.742). Press Enter. The cursor is moved to center of the hole.

5  Move the mouse slowly and a second dimension box appears into which you can type the diameter of the circle (.376). Press Enter. Press Esc to exit the tool.

6  Click the Pull tool in the Edit ribbon group tool then click on the center of the hole so the direction arrows are over the hole.

7  Select the Up To tool guide on the right of the Display window. Move the mouse to the side of the model and roll the middle button to select the hidden surface. When it is highlighted, click. The circle goes to the surface and becomes a hole.

 

 

d   Create an assembly.

1  Click the knob in the Structure tree to make it reappear in the display.

2  Drag with the middle mouse button to spin the model so the knob is on the right and the bracket is on the left.

3  Click the Select tool in the Edit ribbon group, select the surface of the small end of the knob, then Ctrl+click the inside surface of the hole. Click the Center tool in the Assembly ribbon.

The knob moves so its end is aligned with the hole.

 

 

 

 

 

 

4  Click the flat surface of the knob just below the revolve surface.

Move the mouse to the side of the bracket, turn the scroll wheel to highlight the back of the bracket. Ctrl+click the side.

 

 

 

 

 

 

 

 

 

 

 

 

5  Select the Align tool on the Assembly ribbon. The knob slips through the hole in the bracket.

The surfaces that move are those of the model you pick first.

6  Spin the assembly around to see that you assembled the bracket and the knob.

a   Shut off the display of the knob by unchecking it in the Structure panel.

b   Click the Application Menu and select New > Drawing Sheet.

A new window appears with a drawing sheet form that includes the parts of your model in three orthogonal orientation for third angle projection and a format for entering dimensions and general information. Click the Select tool   and move the parts of the model so they are closer together.

c   Make the sheet smaller by clicking on the Detailing tab above the ribbon.

1  Click on the Format tool in the Sheet Setup ribbon.

2  Select Format A Portrait size. The bracket drawing sheet moves to the center of the window in portrait form.

You can toggle between the model and the drawing sheet by using the tabs below the Design window.

a   Enter width of bracket back.

1  Click on the Design tab above the ribbon. To make this easier, zoom into the bracket components by selecting Zoom Box In from the Zoom menu in the Orient ribbon.

2  Click on the Detailing tab again then click on the Dimension tool in the Annotation ribbon.

3  Click on the left edge of the wall of the bracket (bottom left of drawing) then click on its right edge. Do not use the Ctrl key.

A dimension box displays the width of the wall.

4  Move the mouse up (no buttons should be pressed) until the dimension box is located where you want it, then click.

b   Enter the width of the bracket base.

1  Click on the top edge of the bracket base (bottom right of drawing) then click on its bottom edge. Do not use the Ctrl key.

A dimension box displays the width of the base.

2  Move the mouse over (no buttons should be pressed) until the dimension box is located where you want it, then click.

Notice the dimension is the same that you used to create the bracket

c   Enter the height of the bracket back.

1  Click on the bottom edge bracket base (bottom right of drawing) then click on the top edge of its back. Do not use the Ctrl key.

A dimension box displays the height of its back.

2  Click and move the mouse (no buttons should be pressed) until the dimension box is located where you want it then click again.

d   Enter dimensions for the top view of the bracket (top of drawing).

1  Click on the edge of the hole at the end of the bracket.

Move the mouse (no buttons should be pressed) until the diameter of the hole is located where you want it, then click. You may need to click on the arrow to move it to the edge oh the circle.

2  Click on the top of the back of the bracket.

Move the mouse (no buttons should be pressed) to the bottom of the rounded edge. When you move the mouse, many dimensions appear, including the tangent point of the bottom edge. Click and move the dimension until you have placed it where you want it.

Notice the dimension is 4.281, which is what you entered to create the solid.

e   Create a note.

1  Click on the Note tool in the Annotation ribbon.

MB1 where you want the note to be on the drawing and begin to type your note. Press Esc to exit the tool.

2  Click on the Note Leader tool in the Annotation ribbon.  

Mouse over the note to see where you can attach the leader. Click on one of those places and drag. When the leader reaches where you want it to end, release the mouse and press Esc to exit the tool.

3  Create a Material Finish Symbol.

Select the Material Removal Required tool from the Surface Finish list in the Annotation ribbon. Place the mouse where you want to place the symbol, click, then drag to the end of the symbol. Double-click to end the line.

4  Change the design from the drawing.

You can see the solid models in the drawing by pressing the middle mouse button and spinning the drawing.

a   Change the design from the drawing.

1  Change the size of the .3 diameter hole at the bottom of the bracket.

Turn the drawing so you can see inside the hole by clicking the Spin tool in the Orient ribbon group and dragging to spin your design.

Click on the Design tab above the ribbon.

Enlarge the hole by selecting Zoom Box In from the Zoom menu in the Orient ribbon.

Select the Pull tool in the Edit ribbon group then select the inside diameter of the hole. Press and release the spacebar and enter a radius of .2.

Zoom out. The dimension has been changed to .4 on the drawing.

2  Two views of the changed drawing.

To see the drawing view, right-click and select View > Flat View.

To view the whole drawing, right-click and select View > Home.